1## libCEED: Navier-Stokes Example 2 3This page provides a description of the Navier-Stokes example for the libCEED library, based on PETSc. 4PETSc v3.17 or a development version of PETSc at commit 0e95d842 or later is required. 5 6The Navier-Stokes problem solves the compressible Navier-Stokes equations in three dimensions using an explicit time integration. 7The state variables are mass density, momentum density, and energy density. 8 9The main Navier-Stokes solver for libCEED is defined in [`navierstokes.c`](navierstokes.c) with different problem definitions according to the application of interest. 10 11Build by using: 12 13`make` 14 15and run with: 16 17``` 18./navierstokes -ceed [ceed] -problem [problem type] -degree [degree] 19``` 20 21## Runtime options 22 23% inclusion-fluids-marker 24 25The Navier-Stokes mini-app is controlled via command-line options. 26The following options are common among all problem types: 27 28:::{list-table} Common Runtime Options 29:header-rows: 1 30 31* - Option 32 - Description 33 - Default value 34 35* - `-ceed` 36 - CEED resource specifier 37 - `/cpu/self/opt/blocked` 38 39* - `-test_type` 40 - Run in test mode and specify whether solution (`solver`) or turbulent statistics (`turb_spanstats`) output should be verified 41 - `none` 42 43* - `-compare_final_state_atol` 44 - Test absolute tolerance 45 - `1E-11` 46 47* - `-compare_final_state_filename` 48 - Test filename 49 - 50 51* - `-problem` 52 - Problem to solve (`advection`, `advection2d`, `density_current`, or `euler_vortex`) 53 - `density_current` 54 55* - `-implicit` 56 - Use implicit time integartor formulation 57 - 58 59* - `-degree` 60 - Polynomial degree of tensor product basis (must be >= 1) 61 - `1` 62 63* - `-q_extra` 64 - Number of extra quadrature points 65 - `0` 66 67* - `-ts_monitor_solution` 68 - PETSc output format, such as `cgns:output-%d.cgns` (requires PETSc `--download-cgns`) 69 - 70 71* - `-ts_monitor_solution_interval` 72 - Number of time steps between visualization output frames. 73 - `1` 74 75* - `-viewer_cgns_batch_size` 76 - Number of frames written per CGNS file if the CGNS file name includes a format specifier (`%d`). 77 - `20` 78 79* - `-checkpoint_interval` 80 - Number of steps between writing binary checkpoints. `0` has no output, `-1` outputs final state only 81 - `10` 82 83* - `-checkpoint_vtk` 84 - Checkpoints include VTK (`*.vtu`) files for visualization. Consider `-ts_monitor_solution`instead. 85 - `false` 86 87* - `-viz_refine` 88 - Use regular refinement for VTK visualization 89 - `0` 90 91* - `-output_dir` 92 - Output directory for binary checkpoints and VTK files (if enabled). 93 - `.` 94 95* - `-output_add_stepnum2bin` 96 - Whether to add step numbers to output binary files 97 - `false` 98 99* - `-continue` 100 - Continue from previous solution (input is step number of previous solution) 101 - `0` 102 103* - `-continue_filename` 104 - Path to solution binary file from which to continue from 105 - `[output_dir]/ns-solution.bin` 106 107* - `-continue_time_filename` 108 - Path to time stamp binary file (only for legacy checkpoints) 109 - `[output_dir]/ns-time.bin` 110 111* - `-bc_wall` 112 - Use wall boundary conditions on this list of faces 113 - 114 115* - `-wall_comps` 116 - An array of constrained component numbers for wall BCs 117 - 118 119* - `-bc_slip_x` 120 - Use slip boundary conditions, for the x component, on this list of faces 121 - 122 123* - `-bc_slip_y` 124 - Use slip boundary conditions, for the y component, on this list of faces 125 - 126 127* - `-bc_slip_z` 128 - Use slip boundary conditions, for the z component, on this list of faces 129 - 130 131* - `-bc_inflow` 132 - Use inflow boundary conditions on this list of faces 133 - 134 135* - `-bc_outflow` 136 - Use outflow boundary conditions on this list of faces 137 - 138 139* - `-bc_freestream` 140 - Use freestream boundary conditions on this list of faces 141 - 142 143* - `-ts_monitor_turbulence_spanstats_collect_interval` 144 - Number of timesteps between statistics collection 145 - `1` 146 147* - `-ts_monitor_turbulence_spanstats_viewer` 148 - Sets the PetscViewer for the statistics file writing, such as `cgns:output-%d.cgns` (requires PETSc `--download-cgns`). Also turns the statistics collection on. 149 - 150 151* - `-ts_monitor_turbulence_spanstats_viewer_interval` 152 - Number of timesteps between statistics file writing (`-1` means only at end of run) 153 - `-1` 154 155* - `-ts_monitor_turbulence_spanstats_viewer_cgns_batch_size` 156 - Number of frames written per CGNS file if the CGNS file name includes a format specifier (`%d`). 157 - `20` 158 159* - `-ts_monitor_wall_force` 160 - Viewer for the force on each no-slip wall, e.g., `ascii:force.csv:ascii_csv` to write a CSV file. 161 - 162 163* - `-snes_view` 164 - View PETSc `SNES` nonlinear solver configuration 165 - 166 167* - `-log_view` 168 - View PETSc performance log 169 - 170 171* - `-help` 172 - View comprehensive information about run-time options 173 - 174::: 175 176For the case of a square/cubic mesh, the list of face indices to be used with `-bc_wall`, `bc_inflow`, `bc_outflow`, `bc_freestream` and/or `-bc_slip_x`, `-bc_slip_y`, and `-bc_slip_z` are: 177 178:::{list-table} 2D Face ID Labels 179:header-rows: 1 180* - PETSc Face Name 181 - Cartesian direction 182 - Face ID 183 184* - faceMarkerBottom 185 - -z 186 - 1 187 188* - faceMarkerRight 189 - +x 190 - 2 191 192* - faceMarkerTop 193 - +z 194 - 3 195 196* - faceMarkerLeft 197 - -x 198 - 4 199::: 200 201:::{list-table} 3D Face ID Labels 202:header-rows: 1 203* - PETSc Face Name 204 - Cartesian direction 205 - Face ID 206 207* - faceMarkerBottom 208 - -z 209 - 1 210 211* - faceMarkerTop 212 - +z 213 - 2 214 215* - faceMarkerFront 216 - -y 217 - 3 218 219* - faceMarkerBack 220 - +y 221 - 4 222 223* - faceMarkerRight 224 - +x 225 - 5 226 227* - faceMarkerLeft 228 - -x 229 - 6 230::: 231 232### Boundary conditions 233 234Boundary conditions for compressible viscous flows are notoriously tricky. Here we offer some recommendations 235 236#### Inflow 237 238If in a region where the flow velocity is known (e.g., away from viscous walls), use `bc_freestream`, which solves a Riemann problem and can handle inflow and outflow (simultaneously and dynamically). 239It is stable and the least reflective boundary condition for acoustics. 240 241If near a viscous wall, you may want a specified inflow profile. 242Use `bc_inflow` and see {ref}`example-blasius` and discussion of synthetic turbulence generation for ways to analytically generate developed inflow profiles. 243These conditions may be either weak or strong, with the latter specifying velocity and temperature as essential boundary conditions and evaluating a boundary integral for the mass flux. 244The strong approach gives sharper resolution of velocity structures. 245We have described the primitive variable formulation here; the conservative variants are similar, but not equivalent. 246 247#### Outflow 248 249If you know the complete exterior state, `bc_freestream` is the least reflective boundary condition, but is disruptive to viscous flow structures. 250If thermal anomalies must exit the domain, the Riemann solver must resolve the contact wave to avoid reflections. 251The default Riemann solver, HLLC, is sufficient in this regard while the simpler HLL converts thermal structures exiting the domain into grid-scale reflecting acoustics. 252 253If acoustic reflections are not a concern and/or the flow is impacted by walls or interior structures that you wish to resolve to near the boundary, choose `bc_outflow`. This condition (with default `outflow_type: riemann`) is stable for both inflow and outflow, so can be used in areas that have recirculation and lateral boundaries in which the flow fluctuates. 254 255The simpler `bc_outflow` variant, `outflow_type: pressure`, requires that the flow be a strict outflow (or the problem becomes ill-posed and the solver will diverge). 256In our experience, `riemann` is slightly less reflective but produces similar flows in cases of strict outflow. 257The `pressure` variant is retained to facilitate comparison with other codes, such as PHASTA-C, but we recommend `riemann` for general use. 258 259#### Periodicity 260 261PETSc provides two ways to specify periodicity: 262 2631. Topological periodicity, in which the donor and receiver dofs are the same, obtained using: 264 265```yaml 266dm_plex: 267 shape: box 268 box_faces: 10,12,4 269 box_bd: none,none,periodic 270``` 271 272The coordinates for such cases are stored as a new field with special cell-based indexing to enable wrapping through the boundary. 273This choice of coordinates prevents evaluating boundary integrals that cross the periodicity, such as for the outflow Riemann problem in the presence of spanwise periodicity. 274 2752. Isoperiodicity, in which the donor and receiver dofs are distinct in local vectors. This is obtained using `zbox`, as in: 276 277```yaml 278dm_plex: 279 shape: zbox 280 box_faces: 10,12,4 281 box_bd: none,none,periodic 282``` 283 284Isoperiodicity enables standard boundary integrals, and is recommended for general use. 285At the time of this writing, it only supports one direction of periodicity. 286The `zbox` method uses [Z-ordering](https://en.wikipedia.org/wiki/Z-order_curve) to construct the mesh in parallel and provide an adequate initial partition, which makes it higher performance and avoids needing a partitioning package. 287 288### Advection 289 290For testing purposes, there is a reduced mode for pure advection, which holds density $\rho$ and momentum density $\rho \bm u$ constant while advecting "total energy density" $E$. 291These are available in 2D and 3D. 292 293#### 2D advection 294 295For the 2D advection problem, the following additional command-line options are available: 296 297:::{list-table} Advection2D Runtime Options 298:header-rows: 1 299 300* - Option 301 - Description 302 - Default value 303 - Unit 304 305* - `-rc` 306 - Characteristic radius of thermal bubble 307 - `1000` 308 - `m` 309 310* - `-units_meter` 311 - 1 meter in scaled length units 312 - `1E-2` 313 - 314 315* - `-units_second` 316 - 1 second in scaled time units 317 - `1E-2` 318 - 319 320* - `-units_kilogram` 321 - 1 kilogram in scaled mass units 322 - `1E-6` 323 - 324 325* - `-strong_form` 326 - Strong (1) or weak/integrated by parts (0) residual 327 - `0` 328 - 329 330* - `-stab` 331 - Stabilization method (`none`, `su`, or `supg`) 332 - `none` 333 - 334 335* - `-CtauS` 336 - Scale coefficient for stabilization tau (nondimensional) 337 - `0` 338 - 339 340* - `-wind_type` 341 - Wind type in Advection (`rotation` or `translation`) 342 - `rotation` 343 - 344 345* - `-wind_translation` 346 - Constant wind vector when `-wind_type translation` 347 - `1,0,0` 348 - 349 350* - `-E_wind` 351 - Total energy of inflow wind when `-wind_type translation` 352 - `1E6` 353 - `J` 354::: 355 356An example of the `rotation` mode can be run with: 357 358``` 359./navierstokes -problem advection2d -dm_plex_box_faces 20,20 -dm_plex_box_lower 0,0 -dm_plex_box_upper 1000,1000 -bc_wall 1,2,3,4 -wall_comps 4 -wind_type rotation -implicit -stab supg 360``` 361 362and the `translation` mode with: 363 364``` 365./navierstokes -problem advection2d -dm_plex_box_faces 20,20 -dm_plex_box_lower 0,0 -dm_plex_box_upper 1000,1000 -units_meter 1e-4 -wind_type translation -wind_translation 1,-.5 -bc_inflow 1,2,3,4 366``` 367Note the lengths in `-dm_plex_box_upper` are given in meters, and will be nondimensionalized according to `-units_meter`. 368 369#### 3D advection 370 371For the 3D advection problem, the following additional command-line options are available: 372 373:::{list-table} Advection3D Runtime Options 374:header-rows: 1 375 376* - Option 377 - Description 378 - Default value 379 - Unit 380 381* - `-rc` 382 - Characteristic radius of thermal bubble 383 - `1000` 384 - `m` 385 386* - `-units_meter` 387 - 1 meter in scaled length units 388 - `1E-2` 389 - 390 391* - `-units_second` 392 - 1 second in scaled time units 393 - `1E-2` 394 - 395 396* - `-units_kilogram` 397 - 1 kilogram in scaled mass units 398 - `1E-6` 399 - 400 401* - `-strong_form` 402 - Strong (1) or weak/integrated by parts (0) residual 403 - `0` 404 - 405 406* - `-stab` 407 - Stabilization method (`none`, `su`, or `supg`) 408 - `none` 409 - 410 411* - `-CtauS` 412 - Scale coefficient for stabilization tau (nondimensional) 413 - `0` 414 - 415 416* - `-wind_type` 417 - Wind type in Advection (`rotation` or `translation`) 418 - `rotation` 419 - 420 421* - `-wind_translation` 422 - Constant wind vector when `-wind_type translation` 423 - `1,0,0` 424 - 425 426* - `-E_wind` 427 - Total energy of inflow wind when `-wind_type translation` 428 - `1E6` 429 - `J` 430 431* - `-bubble_type` 432 - `sphere` (3D) or `cylinder` (2D) 433 - `sphere` 434 - 435 436* - `-bubble_continuity` 437 - `smooth`, `back_sharp`, or `thick` 438 - `smooth` 439 - 440::: 441 442An example of the `rotation` mode can be run with: 443 444``` 445./navierstokes -problem advection -dm_plex_box_faces 10,10,10 -dm_plex_dim 3 -dm_plex_box_lower 0,0,0 -dm_plex_box_upper 8000,8000,8000 -bc_wall 1,2,3,4,5,6 -wall_comps 4 -wind_type rotation -implicit -stab su 446``` 447 448and the `translation` mode with: 449 450``` 451./navierstokes -problem advection -dm_plex_box_faces 10,10,10 -dm_plex_dim 3 -dm_plex_box_lower 0,0,0 -dm_plex_box_upper 8000,8000,8000 -wind_type translation -wind_translation .5,-1,0 -bc_inflow 1,2,3,4,5,6 452``` 453 454### Inviscid Ideal Gas 455 456#### Isentropic Euler vortex 457 458For the Isentropic Vortex problem, the following additional command-line options are available: 459 460:::{list-table} Isentropic Vortex Runtime Options 461:header-rows: 1 462 463* - Option 464 - Description 465 - Default value 466 - Unit 467 468* - `-center` 469 - Location of vortex center 470 - `(lx,ly,lz)/2` 471 - `(m,m,m)` 472 473* - `-units_meter` 474 - 1 meter in scaled length units 475 - `1E-2` 476 - 477 478* - `-units_second` 479 - 1 second in scaled time units 480 - `1E-2` 481 - 482 483* - `-mean_velocity` 484 - Background velocity vector 485 - `(1,1,0)` 486 - 487 488* - `-vortex_strength` 489 - Strength of vortex < 10 490 - `5` 491 - 492 493* - `-c_tau` 494 - Stabilization constant 495 - `0.5` 496 - 497::: 498 499This problem can be run with: 500 501``` 502./navierstokes -problem euler_vortex -dm_plex_box_faces 20,20,1 -dm_plex_box_lower 0,0,0 -dm_plex_box_upper 1000,1000,50 -dm_plex_dim 3 -bc_inflow 4,6 -bc_outflow 3,5 -bc_slip_z 1,2 -mean_velocity .5,-.8,0. 503``` 504 505#### Sod shock tube 506 507For the Shock Tube problem, the following additional command-line options are available: 508 509:::{list-table} Shock Tube Runtime Options 510:header-rows: 1 511 512* - Option 513 - Description 514 - Default value 515 - Unit 516 517* - `-units_meter` 518 - 1 meter in scaled length units 519 - `1E-2` 520 - 521 522* - `-units_second` 523 - 1 second in scaled time units 524 - `1E-2` 525 - 526 527* - `-yzb` 528 - Use YZB discontinuity capturing 529 - `none` 530 - 531 532* - `-stab` 533 - Stabilization method (`none`, `su`, or `supg`) 534 - `none` 535 - 536::: 537 538This problem can be run with: 539 540``` 541./navierstokes -problem shocktube -yzb -stab su -bc_slip_z 3,4 -bc_slip_y 1,2 -bc_wall 5,6 -dm_plex_dim 3 -dm_plex_box_lower 0,0,0 -dm_plex_box_upper 1000,100,100 -dm_plex_box_faces 200,1,1 -units_second 0.1 542``` 543 544### Newtonian viscosity, Ideal Gas 545 546For the Density Current, Channel, and Blasius problems, the following common command-line options are available: 547 548:::{list-table} Newtonian Ideal Gas problems Runtime Options 549:header-rows: 1 550 551* - Option 552 - Description 553 - Default value 554 - Unit 555 556* - `-units_meter` 557 - 1 meter in scaled length units 558 - `1` 559 - 560 561* - `-units_second` 562 - 1 second in scaled time units 563 - `1` 564 - 565 566* - `-units_kilogram` 567 - 1 kilogram in scaled mass units 568 - `1` 569 - 570 571* - `-units_Kelvin` 572 - 1 Kelvin in scaled temperature units 573 - `1` 574 - 575 576* - `-stab` 577 - Stabilization method (`none`, `su`, or `supg`) 578 - `none` 579 - 580 581* - `-c_tau` 582 - Stabilization constant, $c_\tau$ 583 - `0.5` 584 - 585 586* - `-Ctau_t` 587 - Stabilization time constant, $C_t$ 588 - `1.0` 589 - 590 591* - `-Ctau_v` 592 - Stabilization viscous constant, $C_v$ 593 - `36, 60, 128 for degree = 1, 2, 3` 594 - 595 596* - `-Ctau_C` 597 - Stabilization continuity constant, $C_c$ 598 - `1.0` 599 - 600 601* - `-Ctau_M` 602 - Stabilization momentum constant, $C_m$ 603 - `1.0` 604 - 605 606* - `-Ctau_E` 607 - Stabilization energy constant, $C_E$ 608 - `1.0` 609 - 610 611* - `-cv` 612 - Heat capacity at constant volume 613 - `717` 614 - `J/(kg K)` 615 616* - `-cp` 617 - Heat capacity at constant pressure 618 - `1004` 619 - `J/(kg K)` 620 621* - `-g` 622 - Gravitational acceleration 623 - `9.81` 624 - `m/s^2` 625 626* - `-lambda` 627 - Stokes hypothesis second viscosity coefficient 628 - `-2/3` 629 - 630 631* - `-mu` 632 - Shear dynamic viscosity coefficient 633 - `75` 634 - `Pa s` 635 636* - `-k` 637 - Thermal conductivity 638 - `0.02638` 639 - `W/(m K)` 640 641* - `-newtonian_unit_tests` 642 - Developer option to test properties 643 - `false` 644 - boolean 645 646* - `-state_var` 647 - State variables to solve solution with. `conservative` ($\rho, \rho \bm{u}, \rho e$) or `primitive` ($P, \bm{u}, T$) 648 - `conservative` 649 - string 650 651* - `-idl_decay_time` 652 - Characteristic timescale of the pressure deviance decay. The timestep is good starting point 653 - `-1` (disabled) 654 - `s` 655 656* - `-idl_start` 657 - Start of IDL in the x direction 658 - `0` 659 - `m` 660 661* - `-idl_length` 662 - Length of IDL in the positive x direction 663 - `0` 664 - `m` 665 666* - `-sgs_model_type` 667 - Type of subgrid stress model to use. Currently only `data_driven` is available 668 - `none` 669 - string 670 671* - `-sgs_model_dd_leakyrelu_alpha` 672 - Slope parameter for Leaky ReLU activation function. `0` corresponds to normal ReLU 673 - 0 674 - 675 676* - `-sgs_model_dd_parameter_dir` 677 - Path to directory with data-driven model parameters (weights, biases, etc.) 678 - `./dd_sgs_parameters` 679 - string 680 681::: 682 683#### Gaussian Wave 684 685The Gaussian wave problem has the following command-line options in addition to the Newtonian Ideal Gas options: 686 687:::{list-table} Gaussian Wave Runtime Options 688:header-rows: 1 689 690* - Option 691 - Description 692 - Default value 693 - Unit 694 695* - `-freestream_riemann` 696 - Riemann solver for boundaries (HLL or HLLC) 697 - `hllc` 698 - 699 700* - `-freestream_velocity` 701 - Freestream velocity vector 702 - `0,0,0` 703 - `m/s` 704 705* - `-freestream_temperature` 706 - Freestream temperature 707 - `288` 708 - `K` 709 710* - `-freestream_pressure` 711 - Freestream pressure 712 - `1.01e5` 713 - `Pa` 714 715* - `-epicenter` 716 - Coordinates of center of perturbation 717 - `0,0,0` 718 - `m` 719 720* - `-amplitude` 721 - Amplitude of the perturbation 722 - `0.1` 723 - 724 725* - `-width` 726 - Width parameter of the perturbation 727 - `0.002` 728 - `m` 729 730::: 731 732This problem can be run with the `gaussianwave.yaml` file via: 733 734``` 735./navierstokes -options_file gaussianwave.yaml 736``` 737 738```{literalinclude} ../../../../../examples/fluids/gaussianwave.yaml 739:language: yaml 740``` 741 742#### Vortex Shedding - Flow past Cylinder 743 744The vortex shedding, flow past cylinder problem has the following command-line options in addition to the Newtonian Ideal Gas options: 745 746:::{list-table} Vortex Shedding Runtime Options 747:header-rows: 1 748 749* - Option 750 - Description 751 - Default value 752 - Unit 753 754* - `-freestream_velocity` 755 - Freestream velocity vector 756 - `0,0,0` 757 - `m/s` 758 759* - `-freestream_temperature` 760 - Freestream temperature 761 - `288` 762 - `K` 763 764* - `-freestream_pressure` 765 - Freestream pressure 766 - `1.01e5` 767 - `Pa` 768 769::: 770 771The initial condition is taken from `-reference_temperature` and `-reference_pressure`. 772To run this problem, first generate a mesh: 773 774```console 775$ make -C examples/fluids/meshes 776``` 777 778Then run by building the executable and running: 779 780```console 781$ make build/fluids-navierstokes 782$ mpiexec -n 6 build/fluids-navierstokes -options_file examples/fluids/vortexshedding.yaml -{ts,snes}_monitor_ 783``` 784 785The vortex shedding period is roughly 5.6 and this problem runs until time 100 (2000 time steps). 786The above run writes a file named `force.csv` (see `ts_monitor_wall_force` in `vortexshedding.yaml`), which can be postprocessed by running to create a figure showing lift and drag coefficients over time. 787 788```console 789$ python examples/fluids/postprocess/vortexshedding.py 790``` 791 792```{literalinclude} ../../../../../examples/fluids/vortexshedding.yaml 793:language: yaml 794``` 795 796#### Density current 797 798The Density Current problem has the following command-line options in addition to the Newtonian Ideal Gas options: 799 800:::{list-table} Density Current Runtime Options 801:header-rows: 1 802 803* - Option 804 - Description 805 - Default value 806 - Unit 807 808* - `-center` 809 - Location of bubble center 810 - `(lx,ly,lz)/2` 811 - `(m,m,m)` 812 813* - `-dc_axis` 814 - Axis of density current cylindrical anomaly, or `(0,0,0)` for spherically symmetric 815 - `(0,0,0)` 816 - 817 818* - `-rc` 819 - Characteristic radius of thermal bubble 820 - `1000` 821 - `m` 822 823* - `-theta0` 824 - Reference potential temperature 825 - `300` 826 - `K` 827 828* - `-thetaC` 829 - Perturbation of potential temperature 830 - `-15` 831 - `K` 832 833* - `-P0` 834 - Atmospheric pressure 835 - `1E5` 836 - `Pa` 837 838* - `-N` 839 - Brunt-Vaisala frequency 840 - `0.01` 841 - `1/s` 842::: 843 844This problem can be run with: 845 846``` 847./navierstokes -problem density_current -dm_plex_box_faces 16,1,8 -degree 1 -dm_plex_box_lower 0,0,0 -dm_plex_box_upper 2000,125,1000 -dm_plex_dim 3 -rc 400. -bc_wall 1,2,5,6 -wall_comps 1,2,3 -bc_slip_y 3,4 -mu 75 848``` 849 850#### Channel flow 851 852The Channel problem has the following command-line options in addition to the Newtonian Ideal Gas options: 853 854:::{list-table} Channel Runtime Options 855:header-rows: 1 856 857* - Option 858 - Description 859 - Default value 860 - Unit 861 862* - `-umax` 863 - Maximum/centerline velocity of the flow 864 - `10` 865 - `m/s` 866 867* - `-theta0` 868 - Reference potential temperature 869 - `300` 870 - `K` 871 872* - `-P0` 873 - Atmospheric pressure 874 - `1E5` 875 - `Pa` 876 877* - `-body_force_scale` 878 - Multiplier for body force (`-1` for flow reversal) 879 - 1 880 - 881::: 882 883This problem can be run with the `channel.yaml` file via: 884 885``` 886./navierstokes -options_file channel.yaml 887``` 888```{literalinclude} ../../../../../examples/fluids/channel.yaml 889:language: yaml 890``` 891 892(example-blasius)= 893 894#### Blasius boundary layer 895 896The Blasius problem has the following command-line options in addition to the Newtonian Ideal Gas options: 897 898:::{list-table} Blasius Runtime Options 899:header-rows: 1 900 901* - Option 902 - Description 903 - Default value 904 - Unit 905 906* - `-velocity_infinity` 907 - Freestream velocity 908 - `40` 909 - `m/s` 910 911* - `-temperature_infinity` 912 - Freestream temperature 913 - `288` 914 - `K` 915 916* - `-temperature_wall` 917 - Wall temperature 918 - `288` 919 - `K` 920 921* - `-delta0` 922 - Boundary layer height at the inflow 923 - `4.2e-3` 924 - `m` 925 926* - `-P0` 927 - Atmospheric pressure 928 - `1.01E5` 929 - `Pa` 930 931* - `-platemesh_refine_height` 932 - Height at which `-platemesh_Ndelta` number of elements should refined into 933 - `5.9E-4` 934 - `m` 935 936* - `-platemesh_Ndelta` 937 - Number of elements to keep below `-platemesh_refine_height` 938 - `45` 939 - 940 941* - `-platemesh_growth` 942 - Growth rate of the elements in the refinement region 943 - `1.08` 944 - 945 946* - `-platemesh_top_angle` 947 - Downward angle of the top face of the domain. This face serves as an outlet. 948 - `5` 949 - `degrees` 950 951* - `-stg_use` 952 - Whether to use stg for the inflow conditions 953 - `false` 954 - 955 956* - `-platemesh_y_node_locs_path` 957 - Path to file with y node locations. If empty, will use mesh warping instead. 958 - `""` 959 - 960 961* - `-n_chebyshev` 962 - Number of Chebyshev terms 963 - `20` 964 - 965 966* - `-chebyshev_` 967 - Prefix for Chebyshev snes solve 968 - 969 - 970 971::: 972 973This problem can be run with the `blasius.yaml` file via: 974 975``` 976./navierstokes -options_file blasius.yaml 977``` 978 979```{literalinclude} ../../../../../examples/fluids/blasius.yaml 980:language: yaml 981``` 982 983#### STG Inflow for Flat Plate 984 985Using the STG Inflow for the blasius problem adds the following command-line options: 986 987:::{list-table} Blasius Runtime Options 988:header-rows: 1 989 990* - Option 991 - Description 992 - Default value 993 - Unit 994 995* - `-stg_inflow_path` 996 - Path to the STGInflow file 997 - `./STGInflow.dat` 998 - 999 1000* - `-stg_rand_path` 1001 - Path to the STGRand file 1002 - `./STGRand.dat` 1003 - 1004 1005* - `-stg_alpha` 1006 - Growth rate of the wavemodes 1007 - `1.01` 1008 - 1009 1010* - `-stg_u0` 1011 - Convective velocity, $U_0$ 1012 - `0.0` 1013 - `m/s` 1014 1015* - `-stg_mean_only` 1016 - Only impose the mean velocity (no fluctutations) 1017 - `false` 1018 - 1019 1020* - `-stg_strong` 1021 - Strongly enforce the STG inflow boundary condition 1022 - `false` 1023 - 1024 1025* - `-stg_fluctuating_IC` 1026 - "Extrude" the fluctuations through the domain as an initial condition 1027 - `false` 1028 - 1029 1030::: 1031 1032This problem can be run with the `blasius.yaml` file via: 1033 1034``` 1035./navierstokes -options_file blasius.yaml -stg_use true 1036``` 1037 1038Note the added `-stg_use true` flag 1039This overrides the `stg: use: false` setting in the `blasius.yaml` file, enabling the use of the STG inflow. 1040